I want to save up in buying a sense resistor and just use the PCB tracks. I need to sense up to 2.5A and I wanted to design the trace so it has a 0.1 ohm resistance. Is this a good approach? Also, can anybody share the calculations about how to determine the track length and width assuming a 1 Oz copper thickness?

  • 1
    \$\begingroup\$ This can be done but you will need fine gain and offset trim. Also the first time you have severe over current the trace will vaporize. Also board houses will do their best with dimensions, but if they get it to within 1% that is very good. \$\endgroup\$
    – user105652
    Jun 8, 2018 at 5:23
  • 4
    \$\begingroup\$ It is unlikely to work with any accuracy or repeatability. First copper has a temperature coefficient you have to deal with. Secondly the PCB house will plate the copper providing even more variance. Buy the sense resistor. \$\endgroup\$ Jun 8, 2018 at 5:33
  • 2
    \$\begingroup\$ That's 0.25V drop and 0.6W of power loss. Are you sure you need that much? Typical hall sensors have about 1mOhm resistance, that resolves into 2.5mV feedback. Now, if you OK with that it changes a lot in calculations provided in many answers below. Especially if you do not need high precision. \$\endgroup\$
    – Maple
    Jun 8, 2018 at 6:00
  • 1
    \$\begingroup\$ Thanks guys! I will buy a sense resistors then. Yeah actually 100mohm is too much I will use 47m instead \$\endgroup\$
    – RWeiser
    Jun 8, 2018 at 6:02

6 Answers 6


The two main drawbacks are accuracy related: initial tolerance, and temperature coefficient.

Initial tolerance

PCBs are made to loose tolerances. The copper thickness is nominal, not accurately controlled. Even the etch width is subject to large variations. You might achieve 20% cross-sectional area accuracy to start with if you're lucky, much worse if you're not.

Temperature coefficient (tempco)

Pure metals have a steep tempco, copper is 0.4%/C. That's a 10% change in resistance for a 25C change in temperature. Resistors are made from alloys which have been designed to have near zero tempco.

For detecting whether a current is flowing or not, or perhaps even for the current sense element in a current-controlled converter where it's within a feedback loop, it might be OK. For measuring anything with any semblance of accuracy, use a discrete current shunt resistor.

A discrete resistor will have much higher power handling than a track. And if you should overload it catastrophically, it can be replaced, whereas losing a track would trash the board.


First, let me say that I agree with all the answers already provided. However, with a simple change of requirements this solution might not be as outrageous as it sounds.

The design parameters provided by author resolve into 0.25V drop and 0.6W of power loss. This is way too much, considering that normal current sensors operate from as little as 1~10mV over resistors in 0.6~5mOhms.

If voltage differential of 1-10mV is compatible with whatever circuit is planned then required copper length reduces to centimeters, if not millimeters. Now, if the PCB already has power trace from input to output, why not tap into it for current sense? The voltage differential is already there! The argument that burning that trace will destroy PCB becomes void immediately.

Second most voiced argument is thermal coefficient. Very valid point. However i suspect that power trace on PCB will have much higher thermal dissipation capacity than a resistor. In fact, if done right it will be ambient. Still not precise enough, of course, but we haven't seen the requirements. As @neil-uk pointed out, there are applications where detecting current flow is enough. Or sudden spikes at currents several times above normal (e.g. motor stall).

Another argument is initial trim. Yes, in mass production it won't be plausible. But for one-off project it can be easily done with some careful application of fine sandpaper.

In short, just as others I would not recommend this. But I believe it is doable and acceptable in some specific circumstances.


Was reading app notes and stumbled upon AN894 from Microchip. On page 3 you can find "Figure 3: PCB Shunt Resistor" as a valid option for designs where high precision is not required.

  • \$\begingroup\$ Agree with you. I hope my answer did not come across as saying it couldn't or shouldn't be done. It was more intended to give the OP tools needed to figure out if it would work. \$\endgroup\$
    – user57037
    Jun 8, 2018 at 6:52
  • 2
    \$\begingroup\$ You actually were very helpful. And a little off-topic: I wonder if one day I would see a PCB with all passive components replaced by cleverly arranged traces :D \$\endgroup\$
    – Maple
    Jun 8, 2018 at 8:42
  • 2
    \$\begingroup\$ @Maple that is what is in its core what an integrated circuit is about. Yes we could do this its just not practical at the moment. \$\endgroup\$
    – joojaa
    Jun 8, 2018 at 14:13
  • 2
    \$\begingroup\$ I think that trimming in software is also a very viable solution, in development or even in a production environment. Have the unit measure volt drop, use test jig report actual current and calculate calibration constant(s). Board temperature may be known or perhaps even a useful thing to monitor so the temperature correction can be compensated for as well with not too much code. \$\endgroup\$
    – KalleMP
    Jun 9, 2018 at 16:51
  • 1
    \$\begingroup\$ @Maple you are probably right but OP does not say. I knew of a designer who would spend weeks to try and remove a resistor from a simple garage door key fob to reduce the BOM by a couple of cents. This circuit had a discreet radio circuit and a PCM digital code hopping modulator IC that cost way more than the one resistor. To stay competitive he had to optimise every thing and eventually moved his business and family from South Africa to Spain to reduce cost of shipping this core product to Europe. \$\endgroup\$
    – KalleMP
    Jun 9, 2018 at 17:09

Copper resistors increase in resistance with temperature. It is about 0.4% per degree C. That makes them poor resistors. But perhaps you are OK with it. Just keep in mind that a 25 degree increase in temperature will give you a 10% increase of resistance.

In principal, if you had a way to measure the actual resistance, or a way to know the temperature of the trace, you could compensate for the temperature change. Usually that is not practical.

The way to calculate the resistance of a metal resistor with uniform cross-section is as follows:

R = ρ * l / A.

R is the resistance, ρ is the bulk resistivity of the material, l is the length of the resistor, and A is the cross-sectional area of the resistor. For a trace, the cross-sectional area is trace thickness * trace width.

For copper, ρ is 1.72 * 10^-8 Ohm-meters. So use meters for all your widths and heights and lengths to avoid mistakes with units.

Hope that helps you evaluate whether to use a copper sense resistor and also how to calculate dimensions that might work.


Ok, let's see. There are two things.

First, for 2.5 A ampacity the trace width must be at least 42 mils, according to BITTELE calculator. Now, to get to 0.1 Ohm, the trace length must be about 8.3 inches. I am not sure if the cost of PCB space can offset the cost of a $1 resistor.

Second, there are manufacturing tolerances. The plating thickness may vary, and there is over-etch making the trace narrower. So the value of this shunt will vary from board to board. To get to typical 0.5% - 0.1% chip resistor tolerance, you would need to employ individual calibration of your resistor, which will cost a lot.

Now you decide if this is a good idea to use PCB trace instead of guaranteed $1 SMT resistor.

  • 2
    \$\begingroup\$ Ampacity ratings assume long traces. A short arrow segment connected to wide traces on both ends will use those wider traces as heat sinks and not be heated as much as the ampacity table assumes. \$\endgroup\$
    – The Photon
    Jun 8, 2018 at 14:02
  • \$\begingroup\$ @ThePhoton, for a given set of parameters (copper, 100 mOhms) the 1-oz trace will have aspect ratio of 1:200, no matter how do you slice it or stretch it. This will be a LOOOONG trace, and your remark doesn't apply. \$\endgroup\$ Jun 8, 2018 at 17:12

You can probably do this on a ceramic subtrate pcb. On normal FR4 you can do it, but the tolerance will be bad and the temperature coefficient will be horrible.

For 2.5A, and 0.1 Ohm you'd need 275mm of 1mm trace.

saturn pcb toolkit Saturn PCB toolkit.

However, I recommend a current sense resistor, or a hall effect sensor from Allegro MicroSystems or similar.


The other answers have covered pretty well the how of this. Basically just use a calculator to figure out the trace width and length. But I think these comments are overly cautious. If you're just trying to detect a motor stall, over-current, or something like that I'd say it's fine. I've done this successfully before.

You should figure out what kind of accuracy you need. If it's very low (it should be, given this method), then figure out how much you can reduce the shunt voltage and still get that accuracy. If you start with a low vRef, and then settle for only 10-20 points of resolution you should be able to get the shunt resistance way down.


Your Answer

By clicking “Post Your Answer”, you agree to our terms of service and acknowledge that you have read and understand our privacy policy and code of conduct.

Not the answer you're looking for? Browse other questions tagged or ask your own question.