I am attempting to model a very simple common emitter amplifier for 144Mhz (2 meter HAM band). I found a LTSpice model for a nice RF transistor (MPSH10, 650mhz Ft) since jellybean transistors like the 2N4401 can't really give much gain at this frequency. I thought with this model I should be a more successful at simulating a circuit at higher frequencies.

I wanted to simulate and check the input impedance, and try to set things so the input will match without any matching network (by modifying emitter resistor and current). This is where I'm having trouble understanding something.

To measure input impedance I used the LTSpice current source set to a AC value of 1, so I can just look at the level directly as ohms. I then performed an AC analysis from 120Mhz to 150Mhz

My problem is even with the MPSH10 transistor, for some reason this circuit gives me an input impedance of only 13 ohms. Why?

enter image description here

My emitter current is around 10ma. My Collector voltage is about 7volts.

I'm confused. Because my emitter resistor is bypassed with a capacitor I should only have to take into account little re for emitter resistance -The "conventional" way I've seen the impedance calculated by hand for a Common Emitter circuit is to take the transistor emitter little (re) and do: 25(mv)/Ie to get little re, that would give me 2.5, then multiply by beta to get the base impedance (and then of course put that in parallel with the base resistor bias network). According to LTSpice, if my input impedance is only like 13 ohms that means my beta would only be around 7 or 8. That doesn't make sense at all given this is an RF transistor, the beta should at least be around 50ish, if not higher, at this frequency I would think.

Can you help me understand what I might be doing incorrectly?

This is the model for that transistor, it has exteremely low Base-Collector and Base-Emitter capacitance: enter image description here

I want to understand how to find the input impedance, and have it makes sense to me as to how it's "normally" calculated in common emitter circuits.

I realize a real circuit will have parasitics too and I am greatly simplifying things here.

  • \$\begingroup\$ which node is n005? (It would be better to label the nodes you're going to probe, so we know what node you are showing on your graph) \$\endgroup\$
    – The Photon
    Commented Dec 22, 2020 at 20:21
  • \$\begingroup\$ apologies, I still don't know how to do some things properly in LTSpice. The node being displayed as (n005) is probing the input signal just before the input capacitor, to read the input impedance value \$\endgroup\$
    – niko20
    Commented Dec 22, 2020 at 20:27
  • \$\begingroup\$ According to my simulation on LTspice, your circuit input impedance @144MHz is 90-j14, and this is aproximattely in all 120MHz to 150MHz range \$\endgroup\$
    – GR Tech
    Commented Dec 28, 2020 at 17:05
  • \$\begingroup\$ I somehow got 13ish and you got 90, not sure what I'm doing wrong \$\endgroup\$
    – niko20
    Commented Dec 29, 2020 at 2:37

2 Answers 2


1 nF at 130 MHz is about 1.2 ohms reactance. But as seen at your input, that is multiplied by the transistor beta, so it contributes somewhere in the 10's to 100's of ohms.

If you want to be able to neglect the emitter network in finding the input impedance, you'll need a higher value than 1 nF there.

Also, you wrote,

given this is an RF transistor, the beta should at least be around 50ish,

Not according to the (On Semi) datasheet for MPSH10:

enter image description here

Given this spec, you should only expect a gain of maybe 3-4 at 130 MHz, which isn't far off from what you saw in your simulation.

  • \$\begingroup\$ Well, the main issue is, the input impedance is lower than I would expect, if calculated manually using beta. If the 1nF is higher ohms, that is fine, it would just make the input impedance higher, but right now the impedance is much lower than I would expect. I did just notice that perhaps I'm running too high current for the simulation, I am having a hard time finding the max current for this transistor, many datasheets don't say. So I tried lowering the current to 2ma but the input impedance is still way lower than I would have thought it should be \$\endgroup\$
    – niko20
    Commented Dec 22, 2020 at 20:29
  • \$\begingroup\$ oh wow I guess that is probably right, I will get a pretty low gain after all, even with a 650mhz ft. I think I can live even with a gain of 3, but I just wanted to understand why the impedance doesn't "match up" with predicted. Oh, I see, you are saying the gain will only be about 3 or 4, which is also why my input impedance would be so low. Ok that would make sense. I'm surprised it's so low, sad face.. \$\endgroup\$
    – niko20
    Commented Dec 22, 2020 at 20:32
  • \$\begingroup\$ Here's what I was doing to guess gain: assuming beta was around 250. take frequency of operation and divide it from Ft. So that would be about 4.5. So then take beta and divide by 4.5 - that would give me about 50 beta \$\endgroup\$
    – niko20
    Commented Dec 22, 2020 at 20:37
  • \$\begingroup\$ @niko20, I think what you should do is take the minimum of 250 (the low-frequency beta) and \$f_T/f_{op}\$. \$\endgroup\$
    – The Photon
    Commented Dec 22, 2020 at 20:40
  • \$\begingroup\$ i went back and watched a couple of videos where someone designs an RF preamp and they did exactly that, just did Ft/Fop to estimate beta. Sounds like the rule of thumb. That would match up with what I'm seeing in the simulation, too. \$\endgroup\$
    – niko20
    Commented Dec 22, 2020 at 20:51

Welcome to RF design.

Your problem is that you're treating \$f_T\$ as a hard cutoff, and you're not thinking about all the interelectrode capacitances in a transistor.

First, given a low-frequency current gain of \$h_{FE}\$, the actual current gain is going to be no more than the lower of \$h_{FE}\$ and \$f_T / f_o\$, where \$f_o\$ is your operating frequency. So a really low base impedance is to be expected.

In general you need to use lower impedances all around, and expect lower gain. You should probably also go digging for books on RF circuit design, and if you're not an EE, start backfilling on the information you need. "Experimental Methods in RF Circuit Design" by Wes Hayward is probably a good start. He has a college textbook on RF circuit design, too, which I have and it's excellent (but, I'm an EE, so I'm not in need of backfilling).

Keep in mind that at 144MHz, matching networks won't take up much room. Also keep in mind that the MPSH10, while a nice transistor, was new in the early 1980's -- things have changed since then.

If you don't have it, get a copy of the ARRL Handbook. You may want a copy of "The Arrl Uhf/Microwave Experimenter's Manual", but I can't remember if it goes into circuits, or stops at interconnect and antennas (which aren't trivial subjects at VHF, UHF and microwaves, BTW).

  • \$\begingroup\$ I definitely plan on getting the Experimental methods book! I did see on some YouTube videos where people simply took the Ft and divided it like you said, to get gain value, sounds like the rule of thumb. \$\endgroup\$
    – niko20
    Commented Dec 22, 2020 at 20:49

Your Answer

By clicking “Post Your Answer”, you agree to our terms of service and acknowledge you have read our privacy policy.

Not the answer you're looking for? Browse other questions tagged or ask your own question.