I am considering doing a 4-layer PCB for a 3-phase system (400 V) for the first time (never done a high voltage board before).

Because of mechanical constraints, I want the board to be as thin as possible. It is a reverse stackup, so core is between layer 1 and 2 and then core is also between layer 3 and 4, so between the inner layers (layer 2 and 3) I have prepreg.

On layer 2 there will be a L1 polygon and on layer 3 there will be a L2 polygon directly "above".

How do I know how thin I can make the prepreg material?

During EMC test (surge, burst, etc.) there will be higher than normal voltages between the lines. How do I know how much voltage the prepreg can handle? Is the "voltage endurance" of the prepreg material the same for all types of prepreg materials? Any formula people use?

Should I talk with my PCB manufacturer or how do I find out minimum prepreg thickness? What property does one look at in regards of prepreg to see "voltage endurance"? Any commonly used "rule of thumb"?


1 Answer 1


Yes, ask the fab. If they don't have an answer, check with another, etc. (If this means going with an expensive local or fully-featured fab instead of a budget/proto service, that's well worth the peace of mind -- and the UL/CSA/CE/etc. rating, if applicable.)

Laminate has excellent voltage handling. Consider a standard product such as Isola 370HR: 54 kV/mm breakdown. You might want to be safely under this, say by 4x or more, but that's still only 0.3 mm (400 VAC rounds up to 600 VAC class, category II requires 4 kV; CAT III might also be required for an industrial application).

Standards such as IEC/UL 60950-1* consider inner layers a "cemented joint", at no creepage penalty (or, creepage equals clearance), and clearance determined by breakdown of the material. I don't recall offhand if a safety factor is suggested.

*Deprecated. An industrial product probably follows other standards, anyway; this is just an example I'm somewhat familiar with.

Also, ah, found a copy of 60950-1; there is a specific clause for PCBs (2.10.6), which is a bit more nuanced than my recollection. For example, sheets of prepreg are considered insulating layers, sort of, but evidently not as confidently as for film/sheet insulators (Table 2R: two layers and routine tests for electrical strength (i.e., hi-pot testing), or three or more layers with tests not required; compare with "reinforced", which only requires protection equivalent to two layers of insulation).

From my own experience, I've seen a protoboard, accidentally made with default (~0.18mm) clearances, withstand rectified 480 VAC (i.e. ~650 VDC). There was one failure among four tested pieces, I think. And that was probably a lateral failure (e.g. between hole and inner plane) -- mind that there can be gaps or bubbles in the lay-up, or delamination can occur after soldering or handling. (Some defects can be detected, such as by hi-pot and partial-discharge tests.)

On an unrelated note, mind that the power dissipation of inner layers is poorer than surface copper: the ampacity is generally lower. Ensure adequate conductor width, use multiple layers in parallel, or use heavier copper.


Your Answer

By clicking “Post Your Answer”, you agree to our terms of service and acknowledge you have read our privacy policy.

Not the answer you're looking for? Browse other questions tagged or ask your own question.